Operations
An operation is one machining step: a tool, an area to cut, and how to cut it. The ribbon shows the operation groups the mounted machine can run, so a mill document has no turning operations and a lathe document no 3D milling. A mill-turn shows both.
Operation kinds
| Group | Operations |
|---|---|
| Milling 2D | Face, Contour, Pocket, Slot, Trochoidal slot, Trace, Adaptive, Offset, Engrave, Chamfer, Circular, Thread |
| Milling 3D | 3D Pocket, 3D Finish, Deburr |
| Drilling | Drill, Bore, Probe |
| Multi-axis | 5-Axis Contour, 5-Axis Parallel, Swarf, Adv. Swarf, Rotary Contour, Rotary Parallel, Rotary Offset, Multi-Axis Rough, 5-Axis Flow, Multi-Axis Contour |
| Turning | Facing, Profile Rough, Profile Finish, Groove Rough, Groove Finish, Part, Threading, Chamfer, Taper, Multi-Pass, Form, Bore |
| Plasma | Plasma Profile |
| Wire EDM | Wire Contour |
| Sinker EDM | Sinker Burn, Side Burn |
Each 3D milling kind has its own section, with its settings, defaults and common refusals, in 3D milling operations.
Some kinds carry several strategies. The 3D kinds cover adaptive roughing per level, waterline, parallel, scallop, radial, spiral, morph, flow, pencil and steep/shallow finishing. Drill covers spot, drill, peck, deep, tap and bore cycles, and Detect holes finds the holes in the model for you. Milling operations can also be indexed (3+2) to a tilted plane on a machine that can tilt.
Each 2D milling and hole kind has its own section, with its settings, defaults and common refusals, in 2D milling operations.
The settings tabs
An operation's page groups its settings on tabs. A kind shows only the tabs it has settings for:
- Geometry: the tool and what to cut. Pick faces, edges or loops in the viewport, then set containment, offset, extension and extra or open boundaries where the kind has an area.
- Heights: clearance, retract, top and bottom heights, and where each is measured from.
- Passes: stepover, stepdown, stock to leave and the kind's own strategy settings.
- Lead in / Lead out: how the tool enters, moves between levels and leaves the cut, and the links between cuts.
- Feeds: spindle speed and feed rates.
- Machine: only on the few kinds that drive a machine function of their own.
Edits on a page are pending until you click Apply or Generate. Both are undoable with Ctrl+Z (Cmd+Z on macOS).
Each turning kind has its own section, with its settings, defaults and common refusals, in Turning operations.
What a click picks
Pick buttons use a faint selection tint when idle. An armed button uses the full selection colour and an outline. This marks the active pick target. Hover a selected face, edge or corner in the viewport to highlight its row on the Geometry tab.
Every page that takes a pick from the viewport (operation geometry, boundaries, setup alignment, fixture mates, the work origin) follows the same rule:
- A face is the whole face. Clicking anywhere on a flat face, or on a smooth curved wall, picks all of it, never one of the triangles the model is drawn with.
- An edge is a real model edge: where two faces meet at a crease, or the open border of a sheet. The lines between the triangles inside a face, or around a smooth wall, are never pickable.
- A point is a corner where model edges meet, or the end of an open edge. A vertex inside a face or along a round edge is not a point.
- Only what you can see. A click takes the surface in front, and an edge or a corner only when it is visible there. Nothing behind the part is picked through it; turn the view to reach it.
- Only what the page asks for. Near a feature, a corner wins over an edge and an edge over a face, but only among the kinds the page takes: a plane is picked by a face, so it never snaps to an edge.
Edge mode picks the face between the edges when no edge is under the cursor; Alt+click (Option+click on macOS) picks a single edge segment instead of the whole chain. The same rule holds for picks an AI agent makes over MCP by feature id: an id a click could not have picked is refused by name.
Order
Operations post in the order the browser lists them. Which order to choose, and why, is covered in Order of operations.
Generating
Generate computes the toolpath and checks it. An operation can be in one of three states (shown by its browser icon):
- No toolpath yet: it has never been generated.
- Stale: something it depends on (the model, the stock, the tool, the work offset or its own settings) has changed since it was generated. Generate it again.
- Generated: the cached toolpath matches its inputs.
In the desktop app, a toolpath generates in the background. While it runs, a panel at the top centre of the viewport shows Generating with the operation's name, "(2 of 5)" when more operations wait their turn, the seconds it has run, an activity bar and a Cancel generation button. The panel goes away when the toolpath lands, when generation is refused (the message stays in the status line), or when you cancel. Cancel keeps the old toolpath and drops the operations that wait.
The window stays usable meanwhile: you can turn the view, select and edit. If you edit, undo or delete the operation while it generates, its result is discarded and the status line asks you to generate it again, so an old result never overwrites newer settings. Regenerate all stale still runs in one step, without the panel.
When CamCraft cannot compute a safe path for some part of an operation , it does not hand you a partial or guessed one: generation stops with a message that names the setting or the geometry at fault. Moves the checks flag as unsafe are marked in the viewport, and a message that names a place can be clicked to frame it.
Checking
- Paths ( when hidden) shows every cached toolpath at once.
- Simulate plays the program against the stock with a transport bar; drag the playback slider to jump.
- Deviate compares the machined stock with the model and colours where material is left or where the program cut into the part. Frame rest and Frame gouge take the view to the worst spot of each.
The multi-axis kinds, Probe, Plasma Profile and the EDM kinds (Wire Contour, Sinker Burn, Sinker Side Burn) each have their own reference, with settings, defaults and common refusals: Multi-axis operations, Probing, Plasma cutting and Wire and sinker EDM.
- 2D milling operations - One section per 2D milling and hole kind: what it is for, its key settings and defaults, what it picks, and the refusals you are most likely to meet.
- 3D milling operations - One section per 3D milling kind: what it is for, its key settings and defaults, what it picks, and the refusals you are most likely to meet.
- Probing - The Probe operation: what it finds, its settings and defaults, what it writes into the program, and the guards around the stylus.
- Turning operations - One section per turning kind: what it is for, its key settings and defaults, the tool it takes, and the refusals you are most likely to meet.
- Plasma cutting - The Plasma Profile operation: kerf, cut direction, leads, small holes, the plasma table and post it needs, and the refusals you are most likely to meet.
- Wire and sinker EDM - The Wire Contour, Sinker Burn and Sinker Side Burn operations: the EDM machine and conditions they need, their settings and defaults, and the refusals you are most likely to meet.