CamCraft

Getting started

Your first 4-axis part

This guide makes one small part from start to finish on a Tormach 770MX with a microARC 4 rotary table: a round bar with a flat on each of four faces and a cross slot on one of them. The work is indexed, also called 3+1: the A axis turns the bar to an angle and stops, and then an ordinary 3-axis cut runs. The A axis never turns during a cut.

You need the machine file tormach-770mx-microarc4.mch and the post tormach.cps. Both ship with CamCraft, as the machine Tormach 770MX + microARC 4 and the post Tormach PathPilot.

Companion files in the repository:

  • examples/first-4axis-part.camproj: the finished project.
  • examples/models/first-4axis-part.obj: the model of the finished part.
  • examples/first-4axis-part.nc: the program that the project posts. Each G-code excerpt on this page is copied from this file.

Open the project in the app with Open, or post it from the command line:

camcraft-cli process examples/first-4axis-part.camproj -o first-4axis-part.nc

Continuous 4-axis work, where A turns during the cut, is a different job and is not walked through here. tormach.cps posts it (issue #796). Four hand-written motion tests in the PathPilot simulator confirm the control behavior. The posted continuous program still needs a simulator run and a hardware check. See Continuous 4-axis and What the post refuses below.

The part and how it is held

The stock is a 3/4 in round bar of 6061 aluminium, a minimum of 2.5 in long. Hold it in the microARC 4 chuck with 1.5 in out of the jaws. Each cut is shallow, so a first run has a small risk.

OperationIndexToolCut
Flat A-90G0 A-90T1, 1/4 in flat end millA flat 0.015 in deep, from 1/8 in to 7/8 in from the free end
Flat A0G0 A0T1The same flat on the top face
Flat A90G0 A90T1The same flat, opposite the first one
Flat A180G0 A180T1The same flat, opposite the top one
Cross slot A0G0 A0T2, 1/8 in flat end millA slot 1/8 in wide across the top flat, 1/2 in from the free end, 0.030 in below the bar's skin

The finished bar measures 0.720 in across each pair of flats (0.750 - 2 x 0.015). The cross slot marks the face that was up at A0.

Each flat has round ends, because the 1/4 in tool makes it in one pass along the bar. The flat is 7/8 in to 1/8 in from the free end on its centre line only, and it is about 0.21 in wide. The model first-4axis-part.obj has the same round ends.

CamCraft does not make one setup for each angle. One setup holds all five operations, and each operation carries its own index. See Indexed work for the rules behind this page.

Machine, post and unit

  1. Mount the machine. In the browser, click the Machine row. In the Library list, pick Tormach 770MX + microARC 4. The machine is mounted at once. The machine file states a rotary named A about X with no travel limit (PathPilot treats A as continuous, with no soft limit). It also states nose_to_axis 10.6 (inches, spindle nose to the A centreline at the top of Z). The index swing check uses that number.
  2. Pick the post. In the browser, click the Post row and pick Tormach PathPilot in the list.
  3. Set the unit. Click Stock in the ribbon. In the Units row, choose Inches. The document unit is also the unit of the posted program, so this program starts with G20.

Model, stock and work offset

  1. Import the model. Click Model and pick examples/models/first-4axis-part.obj. An OBJ file has no unit and CamCraft reads its numbers as millimetres. The Stock page shows the model size: 1.5 x 0.75 x 0.75 in. The bar axis is the X axis. The free end is at X 0 and the axis goes through Y 0, Z 0.
  2. Fit the stock. On the Stock page, choose Box, set Fit margin to 0 and click Fit to Models. The stock is now the box that the round bar fits in: Length (X) 1.5, Width (Y) 0.75 and Height (Z) 0.75, with X center -0.75, Y center 0 and Z bottom -0.375. A Cylinder stock always stands along Z, so it cannot be a bar along X. The box touches the bar on the four faces that the job cuts.
  3. Check the work offset. Click Origin. Keep X origin, Y origin and Z origin at 0. The work offset G54 is then at the free end of the bar, on the A centreline.

The work offset must be on the A centreline. tormach.cps writes each indexed cut in the frame of the turned part, and that is correct only when G54 Y0 and Z0 are on the line that the part turns about. On the machine:

  • Set G54 X0 at the free end face of the bar.
  • Set G54 Y0 on the centreline: indicate the two sides of the bar and take the middle.
  • Set G54 Z0 on the centreline: touch the top of the bar and subtract the radius, 0.375 in. Z0 is the centre of the bar, not its top.
  • Mark a line on the top of the bar at A0. The cross slot must cut that line.

Tools

Click Tools, then New tool…. The editor starts with an end mill. Make two tools:

FieldT1T2
NameEM 1/4EM 1/8
Diameter0.250.125
Flute length0.750.375
Shank diameter0.250.125
Spindle rpm60008000
Feed (in/min)158

Choose Add tool for each one. The tools post as T1 and T2, in list order. If your machine's tool table uses other numbers, set Tool number (0 = next free) on each tool. See Tools and tool libraries.

The five operations

Each operation is a Slot from the Milling 2D group: one straight pass between two typed points. For each row of the tables below:

  1. Add a Slot. Set its Tool, and keep Source on Stock.
  2. Click Rename, type the name and choose Apply name.
  3. On the Geometry tab, type the two ends in the Manual section (A X, A Y, B X, B Y) and the Slot width.
  4. On the Heights tab, set the three heights and the Stepdown. For each height, set From to Top of stock and type the Offset.
  5. On the Heights tab, tick Tilted plane (3+2) for an indexed face and type Tool axis A and Tool axis B. Keep Plane origin X, Plane origin Y and Plane origin Z at 0: the plane origin is then on the A centreline. The flat at A0 and the cross slot need no tilt.
  6. On the Feeds tab, type Feed and Plunge feed.
  7. Click Generate.

The index of each operation:

OperationToolTilted plane (3+2)Tool axis ATool axis B
Flat A-90EM 1/4on-900
Flat A0EM 1/4off
Flat A90EM 1/4on900
Flat A180EM 1/4on0180
Cross slot A0EM 1/8off

The cut of each operation (inches):

OperationA X, A YB X, B YSlot widthClearance ZTop ZBottom ZStepdownFeedPlunge feed
Flat A-90-0.75, 0-0.25, 00.250.50-0.0150.015154
Flat A0-0.75, 0-0.25, 00.250.50-0.0150.015154
Flat A90-0.75, 0-0.25, 00.250.50-0.0150.015154
Flat A180-0.75, 0-0.25, 00.250.50-0.0150.015154
Cross slot A0-0.5, -0.16-0.5, 0.160.1250.50-0.030.0182

Keep the other settings at their defaults. A new operation has Coolant on Flood, so the program writes M8.

Three facts explain these numbers:

  • The heights are the same on each face. A tilted operation measures its heights along the tool axis from the plane origin. The plane origin is on the A centreline and the stock box is centred on it, so the top of the stock is 0.375 in from the centreline on all four faces.
  • The slot ends are typed in the tilted plane. For A-90, A90 and A 0 B 180 the plane's X is the machine's X, along the bar. All four flats thus have the same ends (-0.75, 0 and -0.25, 0).
  • The face opposite the top is A 0, B 180. The page accepts Tool axis A from -90 to 90 only; an angle outside -90..90 is refused by name and points to A 0, B 180. Type A 0 and B 180 for that face. The machine check and the post read this pose as A180.

A tilted operation takes typed geometry or a whole model. It refuses a picked face or edge: "a tilted plane cannot yet index a picked selection - pick a whole model instead". That is why this part uses typed slots.

Check it

Click Paths and look at each toolpath: one pass along each of the four faces, and one pass across the top.

When you post, CamCraft runs these checks on the indexed program:

  • The machine check. Each A angle must be in the travel that the machine file states.
  • The index swing. Before each index the program lifts Z to the top of travel. The check makes sure that the tool tip clears the radius that the stock and the part sweep when A turns, with a 5 mm margin. It uses the machine file's nose_to_axis. It does not know your chuck or its jaws.
  • Shank and holder. The tool's shank and holder are read against the stock and the part along the tilted moves.

The stock simulation does not judge a tilted program. Simulate and Deviate report a refusal for the stock, and the post result says:

stock sim did not judge this program: Flat A-90: move 2: posed moves are not modelled by the column engine (its atoms stand upright on +Z; a tilted tool cut upright is a wrong verdict)

This is a statement that the cut was not simulated. It is not a pass. The program still posts. The proof for this part is the PathPilot simulator and an air cut, below. See Checks.

Post the program

Click Post and save first-4axis-part.nc. The status line reports the five operations and repeats the "did not judge" warning. To get a comment on each block, tick Explain G-code (add a comment to each block) on the Post page first.

The program starts in inches, changes to T1 and makes the first index:

(Tormach 770MX + microARC 4)
G20 G17 G90 G91.1 G94 G40 G49 G80
G64 P0.001
(OPERATION: Flat A-90 - SLOT - G54)
G17 G90 G54 G40 G49 G80
(T1 EM 1/4 - FLAT END MILL D0.25)
G53 G0 Z0
G30
T1 M6
G43 H1
G53 G0 Z0
(SPINDLE 6000 RPM NEEDS THE HIGH BELT RANGE)
S6000 M3
M8
(4TH AXIS A ABOUT X - G54 Y0 Z0 ON THE A CENTERLINE)
(NO A CLAMP CODE - RELEASE ANY MANUAL ROTARY CLAMP)
G53 G0 Z0
G0 A-90
G0 X-0.75 Y0
G0 X-0.75 Y0 Z0.875
G0 X-0.75 Y0 Z0.4537
G1 X-0.75 Y0 Z0.36 F4
G1 X-0.25 Y0 Z0.36 F15
G0 X-0.25 Y0 Z0.875
M9
M5

Read it in this order:

  • The index. G53 G0 Z0 lifts Z to the top of travel. Then G0 A-90 turns the table, alone on its line. No A word is on a cutting move.
  • The two notes before the first index tell the operator where G54 must be, and that the program writes no clamp code. The microARC 4 has no clamp.
  • The cut. After the index, Z is the distance from the centreline. The one pass cuts the flat (Z0.36). The bar's skin (Z0.375) is the top of the stock, so no pass runs there: it would cut only air.

The other three flats post the same X, Y and Z lines after their own index. The fourth flat is the A 0, B 180 pose, and it posts as A180:

(OPERATION: Flat A180 - SLOT - G54)
G17 G90 G54 G40 G49 G80
(T1 EM 1/4 - FLAT END MILL D0.25)
G43 H1
G53 G0 Z0
(SPINDLE 6000 RPM NEEDS THE HIGH BELT RANGE)
S6000 M3
M8
G53 G0 Z0
G0 A180
G0 X-0.75 Y0

The cross slot changes to T2. The tool change starts with G30, and a G30 with no axis words moves each axis to the stored G30 position, A included. Thus the operation states its index again after the tool change:

(OPERATION: Cross slot A0 - SLOT - G54)
G17 G90 G54 G40 G49 G80
(T2 EM 1/8 - FLAT END MILL D0.125)
G53 G0 Z0
G30
T2 M6
G43 H2
G53 G0 Z0
(SPINDLE 8000 RPM NEEDS THE HIGH BELT RANGE)
S8000 M3
M8
G53 G0 Z0
G0 A0
G0 Z0.875
G0 X-0.5 Y-0.16

The slot goes down in 0.010 in steps to Z0.345, and the program ends with Z at the top of travel. It writes no G30 and no A move at the end. The last operation is at A0, so the table stays at A0:

G1 X-0.5 Y-0.16 Z0.345 F2
G1 X-0.5 Y0.16 Z0.345 F8
G0 X-0.5 Y0.16 Z0.875
M9
M5
G53 G0 Z0
M30

Prove it in the PathPilot simulator

CamCraft's stock simulation does not judge this program, so run it in a PathPilot simulator before the machine. Tormach's PathPilot HUB has a 770MX simulator.

  1. Start a 770MX simulator. In PathPilot's settings, select the microARC 4 as the 4th axis. Tormach's microARC 4 documents give the steps.
  2. Enter T1 and T2 in the tool table, with a length for each.
  3. Set G54 so that the program has room: Z0 is the centre of the bar, and the cuts are at about Z0.36.
  4. Load first-4axis-part.nc and run it.

Check these points:

  • The program loads with no error and runs to M30.
  • There are five index lines, in this order: G0 A-90, G0 A0, G0 A90, G0 A180, G0 A0.
  • G53 G0 Z0 is the line before each index, and Z is at the top of travel when A turns.
  • A turns only on its own line. The A position does not change during a G1 move.
  • The four flats show as the same short pass at the same X, Y and Z, each at its own A angle.

On the machine

The simulator does not show your chuck, your tool lengths or the direction that your table turns. Do these steps in order:

  1. Check the A direction. In MDI, with the tool well clear, run G0 A90 from A0. The side of the bar that faced you (the front) must come to the top. If the back comes up, stop: the direction is reversed for this post. Do not run the program.
  2. Check the collet nut against the chuck. The flats end 7/8 in from the free end. With 1.5 in of bar out of the jaws, the nut must clear the jaws when the tool is at Z0.36.
  3. Check the swing at the top of Z. Jog Z to the top (G53 G0 Z0) and make sure that the tool tip and the nut clear the bar, the chuck and the jaws through one full turn of A. The index swing check knows only the stock and the part.
  4. Know your G30 position. Each tool change goes to the stored G30 position, and A can turn there. Keep the stored G30 Z at the top of travel, and make sure that the tool clears the part at the stored A.
  5. Air-cut first. Move G54 Z up 1 in and run the program at a low feed and rapid override, in single block. Watch each G0 A line.
  6. Cut. Then put G54 Z back and cut the part. Keep a hand on feed hold. Measure 0.720 in across each pair of flats.

What the post refuses

tormach.cps indexes A between operations. Since issue #796 it also posts an operation that turns A while it cuts (continuous 4-axis, for example Rotary Parallel): A keeps counting past 360, and the moves that turn A run in G93. It refuses these cases by name and writes no file:

CaseThe refusal contains
A changes inside one operation, but the machine file states no A ratesimultaneous 4-axis motion ... states no A feed rate
A keeps turning one way past the A travel (A counts on, PathPilot does not roll it over)A counts on through 360
A tilt that an A about X cannot make (a B or C lean)the A axis about X cannot reach it
An A angle outside the machine file's travelis beyond the A axis travel
An arc in an indexed operationarc on an indexed A ... the indexed frame posts lines only

Continuous 4-axis output for the microARC 4 is new in issue #796. Four hand-written motion tests in the PathPilot simulator confirm the control behavior. The posted continuous program still needs a simulator run and a hardware check. Air-cut a continuous program slowly before you cut with it.

Other limits of indexed work today:

  • Drill does not take a tilt, so a hole on a side face is not a drilling cycle. See Indexed work.
  • The stock simulation does not judge a tilted program (above).

Images to add

When the reproducible UI renders are on main, add these images:

  • The bar, the stock box and the work offset on the A centreline.
  • The Heights tab with Tilted plane (3+2) ticked for Flat A90.
  • The five toolpaths with Paths on.