Tool selection and reach
The principles
Shortest tool that reaches. A tool's stiffness falls with the cube of its unsupported length. Use the shortest tool and the least stick-out (the length from the holder face to the tip) that reaches the deepest feature with clearance for the holder. See Rigidity.
Diameter against the part. A tool cannot cut an inside corner sharper than its own radius, so the smallest inside corner radius limits the largest tool for finishing that corner. Roughing can use a bigger tool; a smaller one then cleans up what is left (rest machining, see Toolpath strategy). In a narrow pocket the tool must also fit the narrowest width with room to move.
Flutes and material. Fewer flutes leave more room for chips, which suits soft, gummy material and deep slots. More flutes allow a higher feed at the same chip load and give a finer finish in harder material. Carbide runs faster and stiffer than HSS but chips more easily under shock.
Holder clearance. The holder is wider than the cutting tool. Reaching down a wall or into a pocket, the holder or shank can hit the part or a clamp before the tip does.
What CamCraft does
A tool stores its diameter, flute length, shank diameter and length, holder diameter and length, flute count, edge material and whether it cuts to centre. A holder can also be a modelled body, a mesh or a drawn profile, and the checks then read the body instead of a plain cylinder.
- Reach is checked at generate time for drilling. A drill may go no deeper into material than its usable flute, and its holder must stay clear of the stock along every move. Both refuse by name, before the path can reach the post.
- Collisions are checked on the simulated program. The simulation flags moves where the shank or holder carries through material, where a move runs the tool through a fixture, and where a rapid goes through stock. The flagged moves are marked in the viewport, and a flagged program does not post.
- Machine tool limits (tool length and diameter the magazine accepts) are checked against the mounted machine when it states them.
What CamCraft does not have is a separate report of "the smallest inside radius in this part against your tool." A tool too large for a corner simply leaves material there; Deviate shows the material left, and rest machining with a smaller tool can take it.
See Operations and the glossary for holder and stick-out terms.