Common workflows
Short how-to recipes, one per task. They are not a reference: each links the page that explains the screen in depth. Every recipe ends the same way: Simulate, Deviate, then Post, which refuses by name if something is unsafe (see Reading a refusal). A passing post is not a guarantee; read the program and dry-run it (Posting).
The recipes use one sample part: testdata/models/Milling-test.step in the
repository, a small STEP model. Any STEP part of your own works the same.
All recipes start the same way: Model to import the part, Stock to describe the block, Origin to place the work offset, Tools > New tool… to make the cutters (First run).
Face the stock top
- On the Stock page pick Box, and use Fit to Models so the block covers the part. Each face of the box has its own allowance: give the top the extra material you want faced off.
- Make a flat or face mill under Tools > New tool…, larger than the pass width you want.
- Add Face (Milling 2D). On Heights, set the top at the stock top and the bottom at the depth to remove. On Passes, set Stepover and Stepdown.
- Click Generate, then Simulate: the tool must clear the whole top of the stock. Deviate shows any material left.
More: Operations.
Square up a block in two setups
- Set up the first side as above: Face, then Contour around the outside, leaving the stock you want to keep for the final pass.
- Setup > Setups > New setup, with Carry stock and WCS over ticked. The new setup starts from a copy of the first one's stock and work offset.
- Re-place the stock and work offset to describe the flipped block (the setup's Settings page has the alignment, including flips such as Flip over X).
- On the new setup's Settings page, set the stock source to what the first setup leaves behind, so verification sees the faced and profiled block.
- Add Face to the final thickness. Generate, Simulate.
- Post writes the program for each setup. CamCraft refuses a carried stock it cannot verify, such as between setups on different machines.
More: Setups.
Pocket and contour a 2D part
- Import the STEP model and set the stock as above.
- Add Pocket (Milling 2D). On Geometry, pick the pocket's floor face or its loop in the viewport (a click picks the whole face).
- On Heights set the bottom at the pocket floor. On Passes set Stepover, Stepdown and Stock to leave so the roughing leaves material for a finish pass.
- Click Generate. Add a second Pocket or a Contour on the same geometry with Stock to leave at zero for the finish pass, and Contour around the outside the same way.
- Simulate and Deviate; the Frame gouge and Frame rest buttons take the view to the worst spots.
Drill and tap a hole pattern
- Add Drill (Drilling). Click Detect holes to find the holes in the model, or pick the hole edges yourself.
- Choose the cycle (Cycle): spot, drill, peck, deep or tap. For peck, set Peck depth.
- Add one operation per tool: a spot drill first, then the drill, then a tap (or a Thread operation under Milling 2D to thread-mill).
- Generate each, Simulate, and Post. Rigid tapping needs a machine that states support for it; a machine without it is refused by name.
Chamfer and deburr edges
- Add Chamfer (Milling 2D) for edges you pick, or Deburr (Milling 3D) to break every edge.
- Use a chamfer tool or a small ball mill; set its size under Tools.
- Generate, then Deviate to check the edge break against the model.
3D rough and finish a surface
- Add Adaptive (Milling 2D) or a 3D roughing strategy under 3D Pocket, with Stock to leave on Passes for the finish.
- Add 3D Finish and choose a strategy (parallel, scallop, waterline, pencil and others). Use a ball mill.
- For rest machining, use the Rest roughing setting on the rougher so it works on what the earlier operation left.
- Generate each, Simulate, Deviate: look for gouge first, rest second.
Turn a simple part on a lathe
- Click the machine button on the Setup group and pick Turning. The ribbon now shows the Turning group.
- Set the stock as a cylinder and the work offset at the chuck or the face.
- Add Facing, Profile Rough, Profile Finish, Groove Rough, Threading and Part, in that order, each with its own tool.
- Generate each in order, Simulate, then Post with the Fanuc Lathe post.
Cut a sheet part
On a router: follow the full walkthrough in
Your first router part
(Sienci AltMill 4x4, grblHAL, corner G54, Drill, 2D Pocket, and 2D Contour
with holding tabs — Tab count, Tab width and Tab height under Lead
in / Lead out — plus RichAuto DSP A11 shop-router notes).
On a plasma table: click the machine button and pick Plasma cutting, add a Plasma Profile, and set Compensation and Direction on its page. Make the torch tool with Kerf width; Pierce height is on the operation's page.
Simulate and Post as usual.
Re-post a job for a different machine
- Open the setup's Machine page and Load machine (.mch), or pick another machine, then pick its post on the Post page.
- Regenerate the stale operations (Regenerate all stale, or Generate on each).
- Post. Read what is refused: a machine-limit refusal names the axis or setting and the limit. Fix the setup, not the limit.
Use the tool library
Tools can export a library (Export library…) and Import library… reads one back, so tools are reused across jobs.
Not yet
Importing a tool library from another system, and a router machine mode
(tabs work today on a mill Contour), are not described here because they
are not on main yet.